Fagor 8025 t cnc 사용자 설명서

107

6.33  G96. S SPEED IN m/min. (feet/min.) AT CONSTANT SURFACE SPEED

When the code G96 is programmed, the CNC assumes that the values entered by S4 are
in m/minute (feet/minute) and the lathe operates in constant surface speed mode.

The CNC assumes as spindle working range the one currently selected. If no range is
selected, the desired range (M41, M42, M43, M44) must be programmed in the same
block.

It is recommended that G96 and S4 spindle speed be programmed in the same block. If G96
is programmed alone, the CNC assumes as Constant Surface Speed the last one used in that
mode. If none was previously used, the CNC will issue error 10.

If the first movement after G96 is made in rapid (G00), to calculate spindle revolutions,
the CNC assumes as part diameter the one at the end of this movement.

If the first movement after G96 is made in G01, G02 or G03, the CNC assumes as part
diameter, the value at the time G96 is executed.

To calculate the number of rev./minute, the CNC will assume as diameter the actual value
when starting G01,G02 or G03.

G96 is modal; i.e. it remains active until G97, M02, M30 is programmed, EMERGENCY
or RESET

When the code G97 is programmed, the CNC assumes that the values entered with S4 are
in rev./minute.

If S4 is not programmed in the same block as G97, the CNC will take as programmed value,
the speed at which the spindle is actually running.

G97 is modal; i.e. it remains active until G96 is programmed.

The CNC assumes G97 on being turned on, after M02,M30, EMERGENCY or RESET.